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Fillets, chamfers, shells and drafts

These features change a body that already exists. Fillet rounds edges, Chamfer bevels them, Shell hollows the body, and Draft tilts faces so a part can leave a mould. You select edges or faces on the model first, then run the command.

Selecting what to change

Pick modes decide what a click selects. The Select tab and the keys switch them: Face (Q), Edge (E), Corner (V), Body (B). The mode named Auto picks whatever is nearest the pointer. See Selecting things.

  • Fillet and Chamfer accept selected edges, selected corners, or two or more selected faces.
    • Edges: each selected edge is rounded.
    • A corner: every edge that ends at the corner is rounded, so rounding a cube corner rounds its three edges.
    • Two or more faces: every edge that two of the selected faces share is rounded. For two faces that is their common edges, including every arc of a ring that is split into arcs. If the faces share no edge, the command says “These faces do not share an edge” and adds nothing.
  • Shell needs one or more selected faces: the faces that are left open.
  • Draft needs one or more selected faces: the faces to tilt.

A command that cannot run is greyed, and its tooltip says why. The messages include “Select edges, or two or more faces, to round”, “Select a second face (or select edges) to round”, “Switch to edge selection to round edges” and “Select one or more faces to leave open”.

Each command is also in the canvas right-click menu: right-click an edge or corner for Fillet and Chamfer, and a face for Fillet, Chamfer, Shell and more.

Fillet

A fillet rounds the sharp edge between two faces with a smooth arc.

  1. Select the edges (or faces) as above.
  2. Choose Home > Modify > Fillet (Shift+F). Chamfer (Shift+B) shares the same button and is in its list: click the small triangle on the button.
  3. The Editor opens with a small radius, so the first preview shows only a slight rounding. Type the radius you want, then confirm with the tick or Enter.

A new fillet starts with a small radius: about 5% of the smallest dimension of the body, rounded to a tidy value (a 40 x 25 x 10 mm body gives 0.5 mm). Change it to the size you need. A new chamfer starts with the same small distance.

OptionWhat it doesDefault
EdgesThe list of edges. Use selection fills it from the model and keeps following the selection until you click Done.The selected edges
RadiusConstant radius in mm. For the Chordal profile it is labelled Chord width.About 5% of the smallest dimension
Variable radiusGives each edge a Start radius and an End radius that blend along it. The start is the end of the edge nearer where you picked it. These two fields take plain numbers, not expressions.Off
ProfileThe cross-section of the round (see below).Circular
Conic ratio (0 to 1)Fullness of a conic round. Shown for Conic.0.5
Shape (0.1 to 1)Shape of a curvature-continuous round. Shown for Curvature continuous (G2).0.5
Tangent chainAlso rounds the edges that continue the selected ones smoothly.On

Profiles.

  • Circular is the usual round, a circular arc.
  • Conic is flatter or fuller than a circle, controlled by the Conic ratio.
  • Chordal is sized by the width of the chord rather than the radius.
  • Curvature continuous (G2) blends into both faces without a visible change in curvature, controlled by Shape.

Tangent chain. With it on, selecting one edge of a rounded outline rounds the whole outline: edges that meet at a vertex and continue each other within 1 degree, and the other arcs of a ring split into arcs. The extra edges are lit before you run the command, and the Editor says “N more edge(s) added through the tangent chain”. Face selections are not chained. The choice is remembered in your browser. Switching it in the Editor re-applies it to the feature’s edge list.

Variable radius rules. Edges that meet at a corner of a variable fillet need the same radius where they meet. A radius of 0 at one end is built as a very small radius.

Corners. Where three rounded edges meet at a convex corner, the kernel adds a spherical patch. If edges meeting at a corner have different radii they end in a mitre, and the feature shows a warning.

Twisted extrudes. A fillet rounds the edges of an extrude with a Twist set (the helical gear and screw shapes) up to about 30 degrees of twist, and a ring of four edges, such as the top of a twisted square, up to about 45 degrees. A chamfer on twisted faces, and rings at 60 degrees and more, are still refused with the reason; reduce the twist or round before twisting.

Not offered: the corner (vertex) chamfer type and the full-round fillet between three faces.

Handle. With an edge selected, a yellow dot appears beside it. Drag it outward for a new fillet, or inward for a chamfer, and release to make the feature. With an edge next to an existing fillet or chamfer, drag the dot to change its size in place. Hold Shift for fine movement, Ctrl for whole millimetres, or type a number while dragging (a minus sign makes a chamfer) and press Enter. Esc cancels. You can switch handles off in the workspace settings.

See fillet in the kernel book.

Chamfer

A chamfer cuts a flat bevel along an edge. Select edges exactly as for Fillet and choose Chamfer (Shift+B).

OptionWhat it doesDefault
Chamfer typeEqual distance, Two distances, or Distance and angle.Equal distance
Distance (Distance 1)The leg of the bevel, in mm. Same default as a fillet radius.About 5% of the smallest dimension
Distance 2The second leg. Shown for Two distances.Same as Distance 1
AngleThe angle between the bevel and the first face, in degrees. Shown for Distance and angle.45
Tangent chainAs for Fillet.On

For Two distances and Distance and angle, Distance 1 is measured on the first face of each picked edge. If the legs end up on the wrong faces, swap the two values. See chamfer.

Shell

Shell hollows the body to a wall thickness and removes the faces you selected, leaving an open box or a cup.

  1. Switch to Face mode and select the faces to leave open.
  2. Choose Home > Modify > Shell (Shift+S).
OptionWhat it doesDefault
FacesThe faces to open. Use selection refills it.The selected faces
Wall thicknessThickness of the walls in mm.The larger of 1 mm and 2% of the smallest dimension, rounded to 0.1
Grow outwardBuilds the walls outward from the existing surface instead of inward.Off

With the shell selected, an arrow on the inner wall changes the thickness when you drag it.

A wall that is too thick for the part fails with “the wall is thicker than the part allows”. The Editor offers Use suggested thickness (N mm), the largest wall that works. Walls also fail where a tight inside curve is smaller than the wall: use a thinner wall, or round the curve first. See shell.

Draft

Draft tilts faces by an angle about a neutral plane. Use it on the walls of a moulded or cast part so it can be pulled out of the tool.

  1. Switch to Face mode and select the faces to tilt.
  2. Choose Features > Modify > Draft (Shift+G).
OptionWhat it doesDefault
FacesThe faces to tilt.The selected faces
AngleDraft angle in degrees.3
Neutral planeThe plane that stays fixed, and whose normal is the pull direction. Pick sets it from a selected face.The plane of the first sketch in the part

Faces keep their names when drafted, so later features still find them. A face parallel to the neutral plane cannot be drafted. An angle that turns an edge over fails with the kernel’s message “edge <faces> turns over”, naming the two faces that meet at the edge: use a smaller angle. Faces that continue a drafted face smoothly are drafted with it. See draft.

To check the result, use Draft analysis on the Evaluate tab. See Surfaces.

You can also taper an extrusion directly with its Draft angle option. See Extrude, revolve, sweep and loft.

Rib and lip

Two more edits sit beside Draft in Features > Modify.

  • Rib adds a thin wall from an open sketch line to the body. Draw a line or chain that reaches the body, then choose Rib. The Editor has Profile and Thickness (about 10% of the smallest dimension at first), and a Rib section with the side of the sketch plane the thickness goes to, a Fillet on the free edge, a Draft angle and, once the part has named bodies, Extend to (the bodies the rib grows to). A line that does not reach the body fails with “does not touch the body”. See rib.
  • Lip / groove adds a raised band along the rim of a flat face, or cuts a groove into it. Select the rim face (Face mode), then choose Lip / groove. It follows every edge of the picked faces. The Editor has Kind (Lip or Groove), Width and Height, both about 5% of the smallest dimension at first. See lip.
  • Split body (Features > Modify) cuts the body at a plane into two bodies, named Base and Lid. With a planar face selected the plane is that face; otherwise it is the standard plane that cuts the smallest side of the body, through the middle. The Editor has Plane (Front, Top, Right, a reference plane, or Pick to take a planar face), Offset along the plane normal, Reverse, the two body names, and Keep (both halves, or only one).
  • Lip joint (Features > Modify) does the same split and also gives the cut a tongue on one half and a groove on the other, for a shelled box and its lid. The Editor adds Tongue on (which half), Tongue height, Tongue width (a fraction of the wall, or millimetres), Centred in the wall (or a distance from the outer wall) and Clearance of the groove (0.2 mm at first), which makes the groove wider on each side and deeper by that much. The preview shows the two halves as you change the numbers. A tongue that does not fit the wall is refused with the reason (inset + width + clearance more than the wall), and a solid body, which has no wall, needs the width and the distance in millimetres.

The two-part case page builds a box and its lid with these and checks the volumes.

A bracket with a rib

This script builds a base plate with four holes, an upright block that carries a round boss with a bore, and a triangular rib that braces the block to the plate. It is the Script tab version of the Rib above, and it shows the things that most often go wrong.

part('Clevis')
  .sketch('top', (s) => s.rrect(140, 90, 8)).extrude(12)                          // plate
  .holes.points(face('>Y'), [[-55, -30], [55, -30], [-55, 30], [55, 30]], { diameter: 10 })
  .sketch('front', (s) => s.rect(30, 79, [15, 45.5])).extrude(60, { mid: true })   // block
  .sketch('front', (s) => s.circle(25, [15, 85])).extrude(60, { mid: true })       // boss
  .sketch('front', (s) => s.line([-50, 12], [-5, 70])).rib(15)                     // rib: ONE open line
  .sketch('front', (s) => s.circle(15, [15, 85])).cut(through(), { direction: 'both' }); // bore

The part is one valid body of about 335,157 mm³. The numbers are written out so the example stands alone; to make them editable, declare them with variables as described in Scripting.

How the rib works:

  • One open line. The rib is drawn as a single line, from [-50, 12] to [-5, 70]. It is centred on the sketch plane and 15 is its total thickness. Both ends are extended until they meet the body, and the result is fused to it, so the line may stop short of the block or lie a little inside the plate.
  • Not a closed triangle. A closed triangle in rib fails with ribNeedsOpenSketch. The opposite mistake is extruding a single open line: that fails with noClosedProfile. For a thin wall made from an open line, use thin on the extrude.
  • Feature order. The rib may come before or after the bore: the web stops at the outer wall of the body and never fills a bore the line runs through, so both orders give the same part.
  • Cut direction. The bore is sketched on the mid-plane of the block, so a cut through everything needs direction: 'both'. Without it the cut goes one way only and may miss.

The rib takes four optional settings, in the GUI and in the script call .rib(thickness, { fillet, draft, side, target, flip }):

SettingMeaning
side'both' (the default) centres the thickness on the sketch plane; 'right' puts all of it on the side the sketch normal points to, 'left' against it.
filletRadius of a round on the two edges of the free edge. It must be less than half the thickness.
draftTaper of the two side faces in degrees (0 to 45): the rib is thickness thick at the free edge and widens toward the body. It needs a sketch that is one straight line.
targetA body name or a list of names. The rib grows to those bodies only; the others are left alone. By default it grows to every body it reaches.

For example .sketch('front', (s) => s.line([-50, 12], [-5, 70])).rib(15, { fillet: 3, draft: 2 }) rounds the free edge of the clevis rib and tapers its sides. A rib on a part with named bodies can grow to one of them with target: 'Bracket'.

Two mistakes to avoid. Extruding one open line fails with noClosedProfile, and the error now says to use Rib for a web or Thin wall for a thin wall. And a through cut from a sketch on the middle of the part cuts one side only unless you give direction: 'both'; the script run warns about it.

When a feature fails

A fillet, chamfer or shell the kernel refuses still opens its Editor as a draft, with a plain-words reason. Cancel removes the draft.

MessageWhat to do
“the rounding runs off the faces beside it”The radius is wider than the neighbouring faces. Use a smaller radius, keep Tangent chain on so the round runs on through corners, or round fewer edges at once.
“the radius is too large for these edges”Use a smaller radius.
“the rounding could not be built”Try a smaller radius, fewer edges at once, or a different order.
“this edge or corner shape cannot be rounded yet”Try fewer edges, a chamfer instead, or leave the rounding to the end of the history.
“the wall is thicker than the part allows”Use a thinner wall, or click Use suggested thickness.
“a face or edge it uses no longer exists”An earlier edit renamed or removed what the feature was built on. Pick the edges or faces again, or undo. See The feature tree and history.

Rounding order matters. Large rounds first, small rounds and chamfers last, and rounds at the very end of the history are the least likely to break when you edit an earlier feature.

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