Keyboard shortcuts

Press ← or → to navigate between chapters

Press S or / to search in the book

Press ? to show this help

Press Esc to hide this help

Your first part

In this tutorial you build a small plate: you sketch a rectangle, give it dimensions, extrude it into a solid, drill a hole, round one edge and save the part. It takes about ten minutes and uses the main ideas of CivilKit CAD. The steps assume the application’s default layout, with the ribbon along the top.

1. Start with a blank part

The application opens with a blank part called Part1, so you can start from it. If you have been working, click New part at the left of the top bar to get a fresh one (it is numbered Part2, Part3 and so on). The shortcut Ctrl+N exists, but browsers often keep it for themselves, so it may not work in a normal browser tab; use the button.

A blank part shows a card titled Start here that says “Pick a plane, then sketch on it.” It has three buttons: Sketch on Front Plane, Sketch on Top Plane and Sketch on Right Plane.

Double-click the part’s name in the top bar to rename it.

2. Sketch a rectangle

  1. Click Sketch on Front Plane. The ribbon is replaced by a single tab named Editing New sketch. The Line tool is already active.
  2. If the view is at an angle, press N (or click Look normal (N)) to turn the view square to the sketch plane.
  3. In the Draw group, click Rectangle, or press R.
  4. Click once to place one corner, move the pointer away, and click again for the opposite corner. A rectangle appears, drawn in blue.

The blue colour means the shape can still move. The chip in the Status group counts the degrees of freedom that are left, for example 4 DOF.

3. Dimension the rectangle

A dimension fixes a size. You will fix the width and the height.

  1. In the Dimension group, click Dimension, or press D.
  2. Click the bottom edge of the rectangle. A value box appears holding the length you drew.
  3. Type 60 and press Enter. The edge is now exactly 60 mm and a dimension label is drawn beside it.
  4. Click the left edge, type 40 and press Enter.

The rectangle’s sides were already kept horizontal and vertical when you drew it. Two freedoms are left: where the rectangle sits on the plane. They do not matter for this tutorial, but you can remove them. Click Fully define in the Status group. CivilKit CAD adds the relations and dimensions it needs to pin the rectangle down and reports how many it added. The chip then reads Fully defined and the lines turn dark.

If a sketch does not behave the way you expect, see When a sketch will not solve.

4. Extrude it

  1. In the Make group of the sketch tab, click Extrude. This finishes the sketch and opens the Extrude editor in the left panel.
  2. The solid appears as a preview. The defaults are Add (selected in the Operation control, next to New body and Cut), an end condition of Blind and a Depth of 10 mm. Leave them.
  3. If the solid grew the wrong way, tick Flip direction.
  4. Click the check mark (Confirm) at the top of the editor.

The ribbon returns to its normal tabs. In the feature tree you now see the Extrude, with its sketch tucked beneath it. Press 7 to look at the part from the Iso view, and Z to fit it in the window.

5. Add a hole

  1. Press Q to choose Face selection.
  2. Click the large flat face on one side of the plate. It lights up.
  3. On the Home tab, in the Create group, click Hole, or press Shift+H.
  4. A new sketch starts on that face with the Point tool active. Click once near the middle of the face to place the hole’s centre.
  5. Click the check mark in the Finish group (Confirm sketch), or press Enter.
  6. The Hole editor opens. The defaults are Simple, size M6, fit Normal and end condition Through. The editor shows the resulting Hole diameter.
  7. Click Confirm.

To move the hole later, double-click its sketch in the feature tree, change the point’s position or dimension it from an edge, and finish the sketch again. For several holes see Holes and threads.

6. Round an edge

  1. Press E to choose Edge selection.
  2. Click one of the four short edges of the plate, the ones that run across its thickness.
  3. On the Home tab, in the Modify group, click Fillet, or press Shift+F.
  4. The Fillet editor opens with a small radius (about 0.5 mm for this plate). Change Radius to 5. Leave Tangent chain on.
  5. Click Confirm.

The corner is now rounded. If you picked the wrong edge, click Undo in the Edit group, or press Ctrl+Z, and try again.

7. Save the part

  1. Click Save in the top bar, or press Ctrl+S.
  2. Your browser either asks where to put the file or downloads it. The file ends in .ckpart.

To save under another name, open More file actions (the three-dot button in the top bar) and choose Save as.

CivilKit CAD also keeps an automatic backup in the browser while you work. After a crash it offers Restore your last session. The backup is a safety net, not a replacement for saving to a file. See Saving and opening.

What you did

Each step is a feature in the tree on the left: the sketch, the Extrude, the hole’s point sketch and Hole, and the Fillet. Double-click any of them to reopen its editor and change a value. CivilKit CAD rebuilds everything after it. Try it now: open the Extrude’s chevron in the tree to reveal its sketch, double-click the sketch to reopen it, double-click the 60 label, type 80, press Enter, and finish the sketch. CivilKit CAD rebuilds the plate and every feature after it.

Next